A reamed bore callout is short, and that is the problem. Most drawings give a diameter with a class, an arrow to the hole, and nothing else, while the features that decide whether the bore can be produced sit in the tolerance block or in nobody's document.
This page lists the six items a reamed bore callout should carry, how to write the size band, what position and form actually belong to, and the note that prevents the most common rework loop.
Six items belong on the callout: diameter with the class or limits, depth or through condition, position with its datum reference, roundness or cylindricity if the function needs it, surface roughness with the cut-off, and the acceptance gauge.
Size and finish are tool requirements. Position belongs to the operation that made the hole, and a callout that assigns it to the reamer will be quoted either as a refusal or as a development programme.
Everything below is about a reamed bore on a machined part. It is not a general dimensioning guide, and it does not replace the drawing standard the customer works to.
What a reamed bore callout has to carry
A callout is a contract between the drawing and the process. It is complete when a shop that has never made the part can choose the tool, set the machine and accept the bore without asking a question.
That is a higher bar than most callouts meet. The common version names the diameter and the class, which is enough to order a reamer and not enough to decide the pre-hole, the fixture or the gauge.
The gap is usually not the drafter's fault. A diameter is easy to specify because it is a single number; a process requirement is harder because it involves two operations and the relationship between them.
The six items below close that gap without turning the drawing into a process sheet. Each one is a property of the finished bore, and each one tells the shop something it would otherwise assume.
The six items on the callout
The table lists the six items, what to write, and what happens when the item is missing. The last column is the one worth reading first, because it describes the failure the item prevents.
| Item | What to write | What happens when it is missing |
|---|---|---|
| Diameter and tolerance | Nominal with the class, or explicit limits, plus the gauge | The shop applies its default band and the bore lands at one end of the tolerance for no stated reason |
| Depth or through condition | Depth with a tolerance, or a through-hole note, plus the usable length | The reaming stage is shorter than the bore and the entry is tapered |
| Position | A position tolerance referenced to the datums the fixture uses | Each supplier assumes location is someone else's responsibility, and the first article is where the assumption surfaces |
| Roundness or cylindricity | A value only where the function needs it | A gauge reads the diameter in one plane and accepts an oval bore |
| Surface roughness | Ra with the cut-off length and the measurement direction | Two parties measure different numbers on the same bore and neither is wrong |
| Acceptance gauge | The instrument, or the measuring method, named on the drawing | The bore passes at the machine and fails at goods-in, and the argument is about the gauge |
Two of the six are frequently over-specified: roundness and position. A roundness value tighter than the function needs adds grinding cost and buys nothing, and a position tolerance that the fixture cannot hold produces a first article that fails for a reason unrelated to the bore.
Two are frequently under-specified: the surface cut-off and the gauge. Both are small pieces of text and both decide whether a passing part is actually accepted.
Size and tolerance: how to write the band
A reamed bore is normally specified by class, for example H7, and the class is expanded to limits in the tolerance block or in a table. That is efficient and it is not ambiguous, provided the class and the nominal are both stated.
The ambiguity appears when a class is used without the nominal, or when a nominal is used with limits that belong to a different class. Both happen when a drawing is edited and one of the two is updated.
For small bores, the class alone may be too coarse for the function. A 6 mm bore with an H7 band is 0.012 mm wide, and a reamer that is ground to the middle of the band leaves half of that on each side for wear and temperature.
For a bore that has to be produced on a specific machine, explicit limits are sometimes clearer than a class, because the shop can compare its gauge reading directly with the drawing instead of with a table.
What the callout cannot do is make a band producible. If the process cannot hold the class, the answer is a different route, not a tighter note; the trade-offs are in reamer tolerance for H7 holes.
Position, form and finish: what the tool can and cannot hold
A reamer holds size and improves form because several edges contact the bore at once. It does not hold position, because it follows the axis of the pre-hole.
That sentence decides how the callout should be split. Size, roundness and finish go on the reaming step; position goes on the operation that establishes the hole, or on a boring pass if the position has to be corrected after the pre-hole.
The split is not always possible on a simple drawing, for example when the bore is called out on a single view with one leader. In that case the position tolerance applies to the finished feature, and the process note has to say which step is responsible for it.
Surface roughness should be written with the cut-off and the direction because a reamed surface is anisotropic. An Ra measured across the feed marks is not the same number as one measured along them, and a callout without the direction leaves the choice to whoever measures first.
The longer explanation of the position and size split is in position tolerance versus size tolerance, which also gives the drawing sentences that separate the two requirements.
The drawing note that prevents rework
Most rework on reamed bores starts with a callout that is complete on size and silent on responsibility. The note below fixes that in two lines and can be added to a drawing without changing the geometry.
"Bore position is established at the pre-hole operation. Reaming is accepted on diameter, roundness and surface finish only. Position to be verified at first article on the pre-hole."
The note works because it assigns each requirement to an operation. It also gives the inspector a sequence: position first, then size and finish, which is the order in which the errors occur.
A second note covers the gauge: "Bore to be accepted with the gauge stated on the drawing; alternative gauges require written agreement." That sentence prevents the goods-in argument that otherwise follows a passing first article.
Both notes are example text. They should be adapted to the customer's drawing standard rather than pasted in unchanged.
Checking the callout before release
Five checks, done in a few minutes, catch most of the defects that reach a supplier.
First, is the nominal present with the class, and do the limits in the tolerance block match the class? A mismatch is the single most common drawing error we see.
Second, is the depth or through condition stated, and does the usable length exceed the bore depth? A reaming stage shorter than the bore produces a tapered entry that no acceptance gauge will forgive.
Third, does the position tolerance reference datums the fixture can touch? A datum that exists only in the model cannot be verified at the machine.
Fourth, is the surface value written with a cut-off and a direction? If either is missing, the number is not yet a specification.
Fifth, is the gauge named? A bore without a stated gauge will be measured twice, in two ways, with two results.
The route that follows the callout is chosen from tolerance and volume, in hole route selection by tolerance and volume, and the cutting side of the decision is in fine boring versus reaming.
What published sources say about this
These pages were used for the definitions and the tool behaviour. Each is cited for what that page states, under its own conditions.
- Dimensioning and Tolerancing (ASME Y14.5): the definitions of position, profile, roundness and runout that a bore callout borrows, and the datum framework a position tolerance references.
- Reamers, machine reamers (toolmaker technical overview): reamer structure, guide part and chamfer lead, the reason a reamer improves form and follows the pre-hole axis.
- Reaming and fine boring (toolmaker competence page): the two finishing tool families and their designs, the reference for what each holds.
- Tools for fine machining bores (toolmaker interview): the single-bladed reamer and the handling effort of fine boring tools, background to the adjust-versus-copy distinction.
- What are the issues for characterization? (NIST/SEMATECH e-Handbook of Statistical Methods): why a requirement has to be defined with the measurement that decides it, the reason a gauge belongs on the callout.
- How are bias and variability controlled? (NIST/SEMATECH e-Handbook): the difference between a gauge that repeats and one that reads correctly, behind the calibration clause.
- What is Process Capability? (NIST/SEMATECH e-Handbook): process spread against specification limits, the test of whether a stated band can be produced at all.
Outbound references are listed because the callout depends on them, not as endorsements. The six-item structure and the drawing notes are HENTRY's convention and are not taken from these sources.
Frequently asked questions
Is a class such as H7 enough for a reamed bore?
It is enough for the tool and not enough for the process. The class fixes the band; the pre-hole, the position requirement and the gauge are still undefined.
Add the position requirement and the gauge, and the callout becomes producible without a conversation.
Should the reaming operation carry a position tolerance?
Only if a boring pass is part of the route. A reamer follows the pre-hole, so a position tolerance on the reaming step describes something the tool cannot influence.
Put the position on the operation that establishes the hole, or add the boring pass and tolerance that.
Why does the surface callout need a cut-off and a direction?
Because a reamed surface is directional. Ra measured across the feed marks differs from Ra measured along them, and a number without the direction cannot be compared.
The cut-off matters for the same reason: a shorter cut-off reports a different value on the same surface.
Does a tighter roundness callout improve the bore?
Only if the function needs it. A reamer normally produces good roundness because several edges support the tool in the bore.
A roundness value tighter than the process can hold adds cost without adding function, and it usually appears on drawings copied from another part.
What should be sent with an RFQ for a reamed bore?
The drawing with the six items, the pre-hole method, the material and heat treatment, the machine and holder, the annual volume and the acceptance gauge.
Use the custom cutting tool RFQ for the package; a callout that carries the six items can be quoted without assumptions.
Updated 13 November 2026: first publication. Scope: the six items a reamed bore callout should carry, how to write the size band, what position and form actually belong to, the two drawing notes that prevent rework and the pre-release checks. Not a general dimensioning guide.