A combination drill-reamer usually makes its own pilot hole, so the real question is not whether a pilot hole is needed. It is which of three locating methods the tool is designed around, and what each one costs at the machine.

We design these tools for aluminium housings, covers and castings, and the locating decision is made before the geometry. This page sets out the three methods, the pilot diameter logic and the four bushing parameters that turn "add a guide" into something a tool grinder can work to.

Most tools called drill-reamers cut the drill stage first, which means the tool carries its own pre-hole: the drill stage is the pilot. A separate pre-hole is needed when the reaming stage leads, when the tool is guided by pads or a bushing, or when the cast skin or an existing core hole would steer a short drill stage.

The three locating methods are a self-centering point, a centre-drilled start and a guide bushing. Pilot diameter follows from the reaming allowance, and the eccentricity of the pre-hole is partly corrected by the drill stage and fully inherited by the reaming stage.

If the bore is deep and blind, the locating question is coupled to chip evacuation and is treated separately in deep blind holes with combination tools. The allowance left for the reaming stage is covered in reaming allowance and pre-hole size.

The wider question, whether the two operations should be combined at all, is screened in when to use a combination drill-reamer.

Does a combination tool need a pilot hole?

The phrase "drill-reamer" describes a sequence, not a single geometry. When the drill stage is at the front, the tool enters a solid or cored hole, drills to a nominal diameter and then opens the same hole to the reaming stage. In that arrangement the drill stage is the pilot, and asking for a separate pre-hole is asking to do the same work twice.

There are three cases where a pre-hole still earns its place. The first is a tool with the reaming stage leading, which happens on some forming and sizing tools where the finished diameter has to be established at the entry.

The second is a tool guided by pads or a bushing, where the guide needs a bore to sit in before the cut starts. The third is a casting with a hard skin, a draft angle or a core shift, where a short drill stage would follow the existing hole instead of correcting it.

What we look at is the ratio between the drill stage length and its diameter, and whether the entry surface is flat. A drill stage with a length of one diameter has very little chance to correct direction; a stage with a length of three diameters has more.

The entry surface matters as much: a machined flat face lets a point start cleanly, a rough cast surface does not.

What we do about it is decide the locating method on the drawing and write it into the process sheet, not into the tool alone. A tool designed to self-center in a machined face will behave differently in a hand-loaded casting with a 2 mm draft.

Where we are careful: a pre-hole adds a station, and the whole argument for a combination tool is that it removes one. Adding a pre-hole to a tool that does not need it gives back the saving before the first chip is cut.

What we are not sure about, without the part, is how much a given core shift will steer a given drill stage. That is a trial question, and the answer is usually visible in the first ten holes.

Three ways the tool finds its position

The choice is a trade between setup time and repeatability. All three methods work; they fail in different places.

MethodWhere it fitsHow it fails
Self-centering drill pointGeneral parts with a machined entry face and a drill stage of at least two diametersFollows an existing core hole or a draft angle; entry wander on rough castings
Centre drill or spotBores that must hold position to the datum, thin or angled entry faces, hard skinAdds a station; a worn spot leaves a cone that steers the drill stage
Guide bushingHigh volume, multi-spindle machines, deep bores, parts that are difficult to indicateBushing clearance becomes part of the position error; chips score the bore

The self-centering point is the default because it costs nothing at the machine. It relies on the drill stage being long enough to damp the entry and on the entry face being flat enough to start. On a machined aluminium housing this is usually true.

The centre drill is the answer when position is called out to a datum and the entry face is not trustworthy. It also helps when the cast skin is harder than the material below it, because the spot removes the skin before the drill stage meets it.

The bushing is the answer when the part cannot be indicated reliably, or when the machine has several spindles that must produce the same bore. It is the most repeatable of the three and the most expensive to set up.

We have seen all three fail for the same reason: the method was chosen for the tool and not for the part. A self-centering point on a casting with a 3 mm core shift will follow the shift. A bushing on a part that is loaded by hand will produce a bore that follows the loading, not the bushing.

Pilot diameter and coaxiality logic

The pilot diameter is set by the reaming allowance, not by the drill catalogue. If the reaming stage removes 0.15 mm on diameter, the drill stage has to leave a hole that is 0.15 mm smaller, within its own tolerance.

The tolerance on the drill stage then becomes part of the allowance budget, which is why item 1 on a combination tool drawing matters as much as the finished bore.

Coaxiality behaves differently at each stage. A pre-hole that is off-centre by a small amount gives the drill stage an off-centre start, and the drill stage can correct part of it because its own geometry pushes against the wall as it cuts. The reaming stage has almost no ability to correct position, because it removes a small radial stock and follows the hole it finds.

The practical rule is that position error is partly corrected by the drill stage and fully inherited by the reaming stage. That is why a combination tool holds position better than two separate operations in the same fixture only when the drill stage has enough length and the pre-hole is stable.

It is also why a combination tool does not rescue a part whose pre-hole moves from piece to piece.

As an illustration, take a pre-hole that is 0.05 mm off the nominal position and a drill stage with a length of two diameters. Part of that offset is taken out by the drill stage, and the remainder is passed to the reaming stage, which copies it.

The split depends on the material, the point geometry and the feed; we do not publish a correction factor, because a number taken from one part would be wrong on the next.

What we ask for on the drawing is the position tolerance at the reaming stage, referenced to the same datum the part uses, and a note on how the pre-hole is produced. Without the second, the first cannot be evaluated.

Bushing design parameters

A bushing is a bearing with a hole in it, and it is designed like one. Four parameters decide whether it helps or hurts: clearance, length, fit and chip path. The values below are industry reference ranges for design discussion, not HENTRY specifications; the bushing supplier's tolerance and the machine builder's recommendation govern.

ParameterReference value for design discussionWhat it controls
Inside diameter clearanceAbout 0.005 to 0.010 mm on diameter for a reaming guide; about 0.02 mm for a drilling guide (industry reference)How much of the tool's position is set by the bushing, and how much by the tool itself
Bushing lengthAt least 2 times the tool diameter, and longer where the tool overhangsAngular guidance; a short bushing controls position but not direction
Outside diameter fitPress fit into the jig plate, or a renewable bush with a linerWhether the bushing moves under load and whether it can be replaced without reworking the plate
LubricationOil or coolant fed to the bushing bore, not only to the cutWear and pick-up on the tool shank, which becomes position error as the clearance opens
Chip pathClearance slots or a relieved exit on the cutting sideWhether chips are carried into the bushing bore and score it

Clearance is the parameter people argue about, and it is the one that is least often measured after assembly. A bushing pressed into a plate changes shape slightly; the bore that was measured on the bench is not the bore the tool sees. That is why we ask for the clearance to be checked in the plate, not in the box.

Length is the parameter that is most often cut for packaging. A bushing that is long enough to guide direction is often longer than the space around the fixture allows, and the compromise is a bushing that holds position at the entry and lets the tool drift below it.

Lubrication is the parameter that is most often forgotten on aluminium. Aluminium picks up on a dry steel bore quickly, and the pick-up reduces the clearance in the same place the tool needs it. Feeding coolant through the bushing rather than only through the tool is a cheap improvement.

For the tool side of the same question, the guide part of a reamer and the chamfer lead are described in the Guhring reaming tools overview. The bushing is doing at the fixture what the guide part does in the tool, and the two should be designed to the same idea.

When a bushing is the wrong answer

A bushing is worth its setup cost when the batch is large enough to amortise it and the part can be presented to it repeatably. Three situations fail that test.

The first is single-part or very small batch work. The fixture, the plate and the bushing have to be made before the first hole, and the setup time is longer than the machining time. A short overhang and a rigid holder will hold position well enough for one part.

The second is a deep cavity where the bushing cannot sit close to the surface. A bushing 40 mm above the cut guides the tool at the top of a long unsupported length, and the tool deflects below it. In that geometry the bushing adds cost without adding position.

The third is a part that is loaded by hand against a stop with visible variation. The bushing locates the tool to the plate, and the plate locates to the part; if the part moves, the bushing holds the tool in the wrong place very precisely.

In all three cases the alternative is the same: reduce overhang, increase holder stiffness and control the entry. That is a machine-side question and is covered in machine-side requirements for PCD reamers. The bushing does not compensate for a machine that cannot present the part consistently.

What we cannot tell from a drawing is which of these three applies. It depends on the fixture, the loader and the batch pattern, and those are usually known to the process engineer rather than to the tool supplier.

Send the hole, the fixture and the batch

For a locating decision we need the hole diameter and depth, the entry face condition, whether a pre-hole or core hole exists and how it is produced, the fixture type, the machine and holder, the batch size and the position tolerance with its datum.

With those we can say whether the tool should self-center, whether a spot is needed, or whether a bushing is worth the setup. The answer changes the tool geometry, so it is worth settling before the drawing is released.

Use the combination drill-reamer page for the tool family and the custom cutting tool RFQ for the drawing and process data. The twelve items a combination tool drawing should contain are listed in combination tool drawing requirements.

What published sources say about this

These are the pages we used for the locating, geometry and measurement points. Each is cited for what that page states, under its own conditions.

  • Reamers, machine reamers (toolmaker technical overview): the reamer guide part, the chamfer lead and the A, B and C shapes, including which shape suits blind holes and which suits through holes.
  • Reaming and fine boring (toolmaker technical page): reaming and fine-boring tools and holders, including guide-pad and floating-holder designs used where bore alignment is the constraint.
  • Dimensioning and Tolerancing (ASME Y14.5): position and datum definitions, which is what a coaxiality callout at the reaming stage is built on.
  • What are the issues for characterization? (NIST/SEMATECH e-Handbook of Statistical Methods): why a position result has to be defined with the measurement that produces it.
  • How are bias and variability controlled? (NIST/SEMATECH e-Handbook): the difference between repeatable and correct readings, the reason a bushing clearance must be checked in the plate.
  • What is Process Capability? (NIST/SEMATECH e-Handbook): process spread against specification limits, which is how a position tolerance should be judged before a fixture is built.
  • What are Control Charts? (NIST/SEMATECH e-Handbook): separating common-cause from special-cause variation, which is how a position shift after a fixture change is read.

Outbound references on this page are limited to pages we opened on 13 November 2026 (Asia/Shanghai). Bushing clearance and length values are industry reference ranges for design discussion, not HENTRY specifications; the bushing supplier's tolerance and the machine builder's recommendation govern. No position or coaxiality value on this page is a HENTRY capability promise.

Frequently asked questions

If the tool drills its own pilot, why does the pre-hole size still matter?

It matters when a pre-hole or core hole already exists, because the drill stage then starts in that hole instead of in solid material. The diameter it finds sets how much material the drill stage removes and how much it can correct direction.

For a cored hole, send the core diameter and its tolerance with the drawing. A core that is nominal on the drawing and 0.4 mm oversize in the casting is a different tool.

How much eccentricity can the drill stage correct?

There is no single number. It depends on the length of the drill stage relative to its diameter, the point geometry, the material and the feed. A longer stage corrects more; a short stage mostly copies what it finds.

What we will not do is quote a correction figure from a different part. The number has to come from the trial or from a measurement on your existing process.

Is a bushing always better than a spot drill for position?

Not always. A bushing is more repeatable when the part presentation is repeatable, and it costs a fixture. A spot drill is cheaper and can be used on a part that is loaded by hand, but it adds a station.

For high volume with a fixed fixture, the bushing usually wins. For one-off parts, the spot or the self-centering point usually wins.

What clearance should we specify for a reaming guide bushing?

Our starting point for discussion is about 0.005 to 0.010 mm on diameter, with about 0.02 mm for a drilling guide. These are industry reference values, not a specification.

The controlling number is the bushing supplier's bore tolerance plus the fit in the plate, measured after assembly. A clearance that is right on the bench can be wrong in the fixture.

Can a combination tool run in a bushing and still cut a tapered bore?

Yes, if the reaming stage does not get enough travel. The bushing holds the tool at the entry, and a short reaming stage finishes before the taper is cleaned up.

The drawing needs the reaming stage length and the bore depth together for this reason; either number alone hides the problem.

Author: Kevin Zeng, Operations Director, HENTRY

Engineering review: Jiack Liu, Engineering Director

Updated 13 November 2026: first publication. Scope: the three locating methods for combination drill-reamers, the pilot diameter and coaxiality logic, and the four bushing design parameters. Bushing values are industry reference ranges, not HENTRY specifications. No position or coaxiality capability is promised on this page.