A combination tool saves a station, and the saving is paid for in the bore. Four things move when drill and ream happen under one clamping: roundness, taper, the entry burr and the exit breakout.

We build these tools, so we have an interest in the saving being real. This page is the other half of the quotation: what the bore gives up, how to measure each cost, and the hole types where the trade does not pay.

One clamping removes position error between two operations, not form error inside the bore. The drill stage leaves a lobed or slightly elliptical section and radial force marks, and the reaming stage, which removes little stock and follows the hole it finds, copies them.

The four costs are roundness, taper, entry burr and exit breakout. Each has a measurement and an acceptance test, and each has a hole type where the cost is larger than the station it saves.

If the question is whether a combination tool suits a specific bore at all, the decision rules are collected in when a combination drill-reamer is the wrong choice. This page deals with the case where the tool is right and the bore still has to be accepted. The upstream screen, whether the two operations should be combined for a part family at all, sits in when to use a combination drill-reamer.

The four quality costs

The table is the acceptance view. It names what moves, why it moves, how we measure it and what the drawing should state. The acceptance values are your drawing values; the page does not supply HENTRY limits.

CostMechanismHow to measureAcceptance test
RoundnessResidual radial force from the drill stage; the reaming stage follows the lobed section instead of correcting itTwo-point or three-point bore gauge at three axial sections, or a roundness instrument; record the section and the planeMaximum radius minus minimum radius at each section, inside the drawing band, compared with the pre-hole reading
TaperReaming stage entry travel too short, or tool deflection at the entryBore diameter in a 1 mm band behind the entry face and at mid-length, in two perpendicular directionsDifference between the entry band and the middle, stated as a single number on the drawing
Entry burrDrill stage exit and reaming stage entry hand over at the same edgeBurr height by profile projector, or a tactile gauge with a known radius; photograph the edge at a fixed magnificationMaximum burr height and the inspection method, with the edge named
Exit breakoutThin wall, cross hole or an interrupted exit at the far endVisual and dimensional check of the breakout zone; wall thickness at the exitPermitted breakout width and depth, or a requirement for a sacrificial support

Two of the four, roundness and taper, are form errors, and they are the ones a combination tool is least able to fix after the cut. The other two, burr and breakout, are edge conditions that can be influenced by geometry and by the process.

Why roundness is the one to watch

A combination tool's real advantage is that the drill stage and the reaming stage share one clamping and one spindle. That removes the position error between two operations, which is often the largest single error on a bored hole. It does not remove the shape the drill stage leaves behind.

A drill stage cutting an aluminium housing produces a section that is not a perfect circle. The point geometry, the two or three cutting edges and the radial force combine to leave a slightly lobed or triangular section, and the amount depends on the feed, the edge sharpness and the stability of the setup.

The reaming stage then enters that section and removes 0.1 to 0.2 mm on diameter, which is not enough to average the lobing out.

Reaming is a low-radial-force operation by design. That is what makes it accurate on size and finish, and it is also why it follows the hole it finds. If the pre-hole is round, the reamed bore is round. If the pre-hole is lobed, the reamed bore is lobed with a better surface finish.

What we look at first on a rejected bore is the pre-hole. If the drill stage produced a round hole and the reamed hole is not round, the cause is usually in the reaming stage: an off-centre chamfer, an unequal margin, or a holder that lets the tool orbit. If the pre-hole is already lobed, the reaming stage is not the place to fix it.

What we do about it is separate the two readings. We ask for the pre-hole roundness and the finished roundness, measured at the same section, because the difference tells us which stage is responsible. Without the first reading, every roundness complaint becomes an argument about the tool.

Where we are careful: a single roundness reading says little. Aluminium moves after unclamping and changes with temperature, so the reading needs a stated time and a stated temperature to be comparable with the next one. The measurement framework for that comparison is the same one described in the NIST/SEMATECH note on measurement characterization.

Taper: the entry that never got a second pass

A tapered bore from a combination tool usually has a simple cause: the reaming stage did not travel far enough into the hole, so the entry was cut by the chamfer lead and the middle was cut by the full diameter. The result is a bore that is slightly smaller in the first millimetre and correct below it.

The cause is in the drawing as often as in the tool. If the reaming stage length is shorter than the bore depth plus the chamfer lead, the stage finishes before the entry is cleaned up. If the tool deflects at the entry because the drill stage is short and the overhang is long, the same taper appears without any length error.

The measurement is deliberately simple: read the diameter in a 1 mm band behind the entry face, then at mid-length, in two perpendicular directions. The difference between the band and the middle is the taper, and it is comparable between tools because the planes are fixed.

What we do about it is check the reaming stage length against the bore depth before the tool is ground, and check the overhang against the tool diameter at the same time. Where the two conflict, the fix is usually a longer reaming stage or a shorter overhang, not a change in the cutting data.

Where we are not certain: taper that appears only on the last parts of a batch is usually wear, not geometry. A new tool that cuts a tapered entry and a worn tool that cuts the same taper are two different problems, and the second one belongs in the wear discussion rather than in the drawing review.

The definitions of roundness, cylindricity and runout that the acceptance test relies on are set out in ASME Y14.5 dimensioning and tolerancing. Using the same definition on the drawing and at the gauge is what makes a taper reading comparable between two suppliers.

Burr and breakout at the edges

Both edges of the bore are produced by a handover. At the entry, the drill stage exits and the reaming stage enters at almost the same place. At the exit, the drill stage breaks through and the reaming stage follows, often into a thinner wall or a cross hole.

The entry burr has three sources. The first is the drill stage's own exit burr, which forms as the point breaks into the region the reaming stage will later finish.

The second is the reaming stage's chamfer lead, which can push material ahead of it instead of cutting it. The third is the handover itself, where the two chamfers do not meet and leave a ring of material that neither stage cuts cleanly.

The exit breakout has a different cause: support. A drill stage breaking out of a thin wall or into a cross hole has nothing behind the edge, and the material tears rather than shears. A reaming stage following the same path does not repair the tear; it often widens it.

What we do about it is decide the edge condition on the drawing, not at first article. A permitted burr height with a named inspection method, plus a note on whether a sacrificial support or a back chamfer is allowed, removes most of the argument. Without those, the part is judged by eye and the judgement changes with the inspector.

Aluminium makes both edges more sensitive than steel because the material is more ductile, and the cast or wrought route changes the burr form rather than removing it. The process side of the same question is covered in the burr-control notes for aluminium exit burr control in reaming.

For edge geometry direction, the reamer structure and chamfer lead described in the Guhring reaming tools overview is the starting point; guide-pad and floating-holder options that change the entry behaviour are described in the MAPAL reaming and fine boring pages.

When the trade is not worth it

Three hole types consistently cost more than the station they save. They are worth naming because each one is visible on the drawing before a tool is quoted.

The first is a roundness requirement below 0.01 mm. At that level the pre-hole has to be controlled as tightly as the finished bore, and a drill stage cannot deliver it. A separate pre-hole operation, or a different finishing process, is the honest route.

The second is a blind hole with a depth-to-diameter ratio above 5. The reaming stage needs travel at the bottom of the hole, the chip has to leave through a long path, and the drill stage has very little room to correct direction. The combination saves a station and adds a scrap risk.

The third is a cross hole whose exit falls inside the reaming stage travel. The reaming stage meets an interrupted cut at the worst point, and the breakout appears in the finished bore rather than in a roughing operation.

In those cases the answer is not a better combination tool. It is two operations, or a different process. Saying so costs us a quotation and saves the customer a batch.

What we cannot do is predict the size of the cost from the drawing alone. The same hole in the same material can be acceptable on one machine and not on another, because stability, holder and coolant delivery decide how much of the drill stage's form error survives.

That is why we quote a first article and measure it rather than promising a number in advance.

Send the hole type and the cycle time

Send the hole diameter and depth, the material and temper, the hole type (through, blind, cross hole, thin wall), the roundness and taper requirement, the burr requirement, the machine and holder, the coolant method and the cycle time you are trying to reach.

With those we can say which of the four costs is likely to bind, and whether the saving is real for that bore. If the answer is that the trade does not pay, we will say so before a tool is quoted.

Use the custom cutting tool RFQ for the part data and the combination drill-reamer page for the tool family. The drawing items that decide most of these costs are in combination tool drawing requirements, and the locating decision is in pilot hole and bushing design.

What published sources say about this

These are the pages we used for the geometry, material and measurement points. Each is cited for what that page states, under its own conditions.

  • Reamers, machine reamers (toolmaker technical overview): reamer structure, guide part and chamfer lead, and the A, B and C shapes, including the interrupted-cut case that quick-helix reamers are made for.
  • Reaming and fine boring (toolmaker technical page): reaming and fine-boring tools and holders, including guide-pad and floating-holder designs used where bore alignment or form is the constraint.
  • Dimensioning and Tolerancing (ASME Y14.5): the definitions of roundness, cylindricity, runout and profile that an acceptance test has to use if two suppliers are to agree.
  • What are the issues for characterization? (NIST/SEMATECH e-Handbook of Statistical Methods): why a form reading needs a defined measurement before it can be compared with the next one.
  • What is Process Capability? (NIST/SEMATECH e-Handbook): process spread against specification limits, the frame for deciding whether a roundness requirement is achievable at all.
  • What are Control Charts? (NIST/SEMATECH e-Handbook): separating common-cause from special-cause variation, which is how a taper that appears late in a batch should be read.

Outbound references on this page are limited to pages we opened on 13 November 2026 (Asia/Shanghai). All acceptance values are drawing values, not HENTRY limits. No roundness, taper or burr value on this page is a HENTRY capability promise; the 0.1 to 0.2 mm radial stock and the depth-to-diameter threshold of 5 are working figures for discussion.

Frequently asked questions

Can a combination tool hold roundness as well as a separate reaming operation?

It can hold the same roundness if the pre-hole is as round as the separate operation's pre-hole. The tool does not add form error by itself; it fails to remove the form error the drill stage leaves.

Where the separate operation wins is when the pre-hole can be made round before reaming, for example by boring. That extra operation is the cost the combination tool was meant to remove.

How do we tell a taper from a roundness problem?

A taper changes with axial position: the entry band is a different size from the middle. A roundness problem changes with angle at the same axial position.

Measure both: two diameters along the axis for taper, and a maximum-minus-minimum at one section for roundness. A single two-point reading in one plane cannot separate them.

Is the entry burr worse with a combination tool than with two operations?

It is different. With two operations the drill burr is removed or pushed aside by the reaming stage, and the reaming stage leaves its own small burr. With one tool the two edges hand over at the same place, so the burr can be a combination of both.

The practical difference is that the handover is harder to see on the drawing, which is why the burr requirement needs a named edge and a method.

Why does the bore measure well in the fixture and badly after unclamping?

That is usually clamping or residual stress, not the tool. Aluminium moves when the clamp is released, and a thin wall moves more.

Measure free, at a stated temperature and a stated time after machining, and compare with the clamped reading. If the two differ, the tool is being blamed for the fixture.

At what depth-to-diameter ratio should we stop considering a combination tool?

Above about 5 for a blind hole, the chip path and the reaming travel start to dominate, and the scrap risk usually outweighs the saved station. That figure is a working threshold for discussion, not a rule.

Between 3 and 5 the answer depends on the material and the coolant delivery, and it is worth a trial before a batch decision.

When the trade-off shows up as a first-article failure rather than a design choice, the sequence of containment, root cause and closure is in nonconformance and 8D for cutting tools.

Author: Kevin Zeng, Operations Director, HENTRY

Engineering review: Jiack Liu, Engineering Director

Updated 13 November 2026: first publication. Scope: the four quality costs of a combination drill-reamer, how each is measured, the roundness and taper mechanisms, and the hole types where the trade does not pay. Acceptance values are drawing values; no HENTRY capability is promised.